Home / Processes
Inconel Machining Processes: Turning, Milling, EDM and Grinding
Nickel superalloys punish the wrong process choice. This is how shops that run Inconel regularly split a part between the lathe, the mill, the EDM and the grinder.
Why process choice matters more on Inconel
On aluminum or mild steel, a slightly wrong process costs a few minutes. On a nickel superalloy it can cost a part. Three properties drive almost every decision a shop makes.
- Heat at the edgeInconel 718 conducts heat at roughly 11 W/m·K, against about 16 for 304 stainless and around 50 for carbon steel. Heat that would leave with the chip stays in the tool, so cutting speeds sit far below what the same shop runs on steel.
- Work hardeningA dull edge or a light rubbing pass hardens the surface layer, and the next pass has to cut through it. Shops keep feed per tooth up and avoid dwelling in the cut. Why Inconel work-hardens
- Strength at temperatureThe alloy keeps its strength at the temperatures the cutting zone reaches. That is the property buyers want in service and the reason tool loads stay high on the machine.
Process, part feature and what to expect
Typical ranges on nickel superalloys, not promises. Geometry, alloy condition and part size move them. The shop that quotes you confirms what it can hold on your drawing.
| Process | Typical features | Typical tolerance | Typical finish |
|---|---|---|---|
| CNC turning | Shafts, rings, bushings, seal seats, external threads | ±0.02 to ±0.05 mm | Ra 0.8 to 1.6 µm |
| 3-axis and 5-axis milling | Housings, brackets, manifolds, impellers, flanges | ±0.02 to ±0.05 mm | Ra 1.6 to 3.2 µm |
| Drilling and gundrilling | Bolt holes, coolant and gas passages, long bores | Position ±0.05 mm | Ra 1.6 to 3.2 µm |
| Thread milling and tapping | Internal threads, large or blind threads | Class 6H / 2B | As machined |
| Wire EDM | Sharp internal corners, slots, thin ribs, fir-tree profiles | ±0.005 to ±0.01 mm | Ra 0.4 to 1.6 µm with skim passes |
| Sinker and small-hole EDM | Blind cavities, small cooling holes, start holes | ±0.01 to ±0.02 mm | Ra 0.8 to 3.2 µm |
| Cylindrical and surface grinding | Bearing journals, sealing faces, gauge diameters | ±0.005 to ±0.01 mm | Ra 0.2 to 0.4 µm |
How each process handles nickel alloys
What shops that run Inconel regularly do differently from a general job shop.
- TurningRigid setups, positive-rake coated carbide for finishing and ceramic inserts (SiAlON or whisker-reinforced) for roughing on larger diameters. Carbide finishing speeds on aged 718 typically sit around 20 to 60 m/min; ceramic roughing runs several times faster but needs a stable cut with no interruptions.
- MillingTrochoidal or constant-engagement toolpaths keep radial load and heat steady. Five-axis machines help on impellers and blisks because a shorter tool deflects less. Expect more tool changes per part than on steel. Tooling compared
- DrillingThrough-spindle high-pressure coolant, carbide drills and peck cycles only where chip evacuation needs them, since every peck re-enters work-hardened material. Long passages go to gundrilling.
- ThreadingThread milling is the default for internal threads in aged material. A thread mill that breaks leaves a recoverable part; a broken tap usually does not. External threads are single-point turned or rolled on softer grades.
- Wire and sinker EDMEDM ignores hardness, so it handles aged parts, sharp internal corners and thin walls that would deflect under a cutter. The trade-off is speed and a recast layer that skim passes reduce. EDM vs CNC for Inconel
- GrindingThe route to the tightest diameters and flattest faces, usually as the last step after heat treatment. Shops use sharp, open-structure wheels and plenty of coolant to avoid burning the surface.
Background reading: electrical discharge machining on Wikipedia.
Which process for which feature
If your drawing has one of these, expect the quote to include the process on the right. Knowing it in advance helps you read the price.
| Feature on the drawing | Usual route |
|---|---|
| Internal corner sharper than R0.5 mm | Wire EDM or sinker EDM. A milling cutter leaves its own radius. |
| Bore at H7 or tighter, long engagement | Boring to near size, then honing or internal grinding. |
| Holes under about 1 mm diameter | Small-hole EDM drilling. Twist drills break or walk in nickel alloys at this size. |
| Hole depth over about 10 x diameter | Gundrilling or EDM, with straightness called out on the drawing. |
| Internal thread in aged 718 or Waspaloy | Thread milling. A broken tap in a hard nickel part often means scrapping it. |
| Wall under about 1 mm | Wire EDM for the final profile, or light finishing passes with support fixturing. |
| Sealing face flatness under 0.01 mm | Surface grinding or lapping after machining and heat treatment. |
Design notes that cut machine time
Small drawing changes save more on Inconel than on any common metal, because every minute of cutting costs tool life too.
- Corner radiiGive internal corners the largest radius the design allows. R1 mm or more lets a sturdier cutter do the work instead of EDM.
- Tolerance where it countsHold ±0.02 mm only on functional features. General features at ±0.05 mm or ±0.1 mm remove finishing passes. Tolerances you can hold on Inconel
- Thread depthThread engagement beyond about 1.5 x diameter adds little strength and a lot of tool risk in nickel alloys.
- Heat treat conditionState the final condition and whether finishing must happen after aging. It decides the whole process sequence. 718 heat treat sequencing
- Surface integrityIf the part is fatigue-critical, say whether recast from EDM is allowed and what surface finish applies to which faces.
Inspection and paperwork to ask for
The matched shop runs its own inspection. Put the documents you need on the RFQ so the quote includes them from the start.
- Mill certificateHeat number traceability back to the melt for the bar, plate or forging used.
- PMIPositive material identification on incoming stock or finished parts, so a substitute alloy cannot slip through. Mill certs and PMI
- Dimensional reportCMM or manual inspection report on critical features, on every lot or the first article only.
- First article inspectionA full FAI report, often in AS9102 format for aerospace work. What an FAI covers
Questions about Inconel machining processes
Which CNC process is cheapest for an Inconel part?
Turning, when the geometry allows it. A round part on a lathe usually has the shortest cycle time and lowest tool cost. Milling comes next. EDM and grinding are slower per feature, so they are best kept to the features that actually need them.
Does EDM damage the surface of Inconel parts?
EDM leaves a thin recast layer and a heat-affected zone. Skim passes reduce it to a few microns. On fatigue-critical aerospace parts the drawing often limits recast depth or requires its removal, so state that limit on the RFQ if your part has one.
Should my part be machined before or after heat treatment?
For age-hardenable grades like 718, X-750 and Waspaloy, shops usually rough in the solution-treated condition, age, then finish critical features. Solid-solution grades like 625 and 600 have no aging step, so they are usually machined in the annealed condition throughout.
What tolerance should I put on an Inconel drawing?
Around ±0.05 mm on general features and ±0.02 mm on functional ones is a sensible default. Tighter is possible with grinding or EDM, but each step tighter adds machine time on a material that work-hardens with every pass.